Damatech
High Performance SteelValue Added ProcessingInnovative Industrial SolutionsDamatech

Toolox® Machining

Milling a Toolox® block on a machining centre

Machining recommendations for Toolox®

Toolox® is a modern quenched and tempered prehardened engineering and tool steel, delivered with measured and guaranteed mechanical properties. The basic idea is to save you time by delivering Toolox® heat treated and ready to use. It provides you with lower costs, reduced risks and saves you valuable time in your production process due to its excellent machinability.

Toolox® is based on the same low carbon content as in Hardox® and Strenx®, but it is specially developed for tools and machine components working at high temperatures. It has excellent fatigue properties, and you can increase the surface hardness with nitriding or PVD coatings to gain more control over the service life of your tools or components.

Machined Toolox® tools and machine components

Shorter lead time from concept to production

In the information that follows, you will find our recommendations of tools to process Toolox®. Similar tools from other suppliers might work, but here are the ones we have tested so far.

All content in this brochure should be considered as recommendations. Machining contains many different parameters that can and will affect the end result. Optimization of cutting data should always take place at the machine to be used for manufacturing.

Toolox® plate and round bar stock

Drilling recommendations

It is recommended to use drills with an internal coolant supply when drilling Toolox®. Internal coolant:

  • Is always to be preferred to avoid chip jamming.
  • Should always be used at hole depth above 3 times the drill diameter.
  • Never use a HSS drill with external cooling in a horizontal drilling machine.
  • Coolant mix 8 – 12%.

To make a hole with a tight tolerance, a good surface finish and a long service life of the drill, the following is required:

  • Make sure that the runout on the drill is as small as possible. For solid carbide drills, the runout should not exceed 0,02 mm.
  • Use the shortest possible drill for maximum stability.
  • Chip breaking and chip evacuation must always be good.
  • Coolant supply and pressure need to be satisfactory.
  • A collet and tool shank in bad condition will ruin an otherwise perfect setup.
  • The machine should be in good condition.
  • A good clamping of the workpiece is necessary.

Formulas and definitions, drilling

  • Vc = Dc × π × n / 1000
  • n = Vc × 1000 / (π × Dc)
  • Vf = fn × n
  • Vc = cutting speed (m/min)
  • n = spindle speed (rpm)
  • fn = feed per revolution (mm/r)
  • Vf = penetration rate (mm/min)
  • Dc = drill diameter (mm)

Solid cemented carbide drill

First choice for smaller diameter and when closer diameter tolerance is required. Works well for short or relatively deep holes. The drill is sensitive to vibrations and should be used together with high precision chucks.

Solid cemented carbide drill. Cutting data by drill diameter. Columns give drill diameter, (Dc), mm / Feed per revolution, (fn), mm/rev.


Steel grade

Cutting speed (Vc), m/min

Ø 3,0 – 5,0 mm — Min - Max

Ø 3,0 – 5,0 mm — Start value

Ø 5,01 – 10,0 mm — Min - Max

Ø 5,01 – 10,0 mm — Start value

Ø 10,01 – 15,0 mm — Min - Max

Ø 10,01 – 15,0 mm — Start value

Ø 15,01 – 20,0 mm — Min - Max

Ø 15,01 – 20,0 mm — Start value

Toolox® 33

65 – 90

0,08 – 0,15

0,10

0,09 – 0,16

0,12

0,16 – 0,22

0,18

0,22 – 0,28

0,25

Toolox® 40

50 – 65

0,06 – 0,12

0,08

0,08 – 0,15

0,11

0,16 – 0,20

0,16

0,16 – 0,24

0,20

Toolox® 44

40 – 60

0,06 – 0,11

0,07

0,08 – 0,13

0,10

0,12 – 0,18

0,15

0,16 – 0,20

0,18

Long hole drilling with 16 – 20 × Dc

Clamping of this type of drill should be done with high precision chucks. Possible hole tolerance H8-H9. Cutting fluid pressure > 20 bar.

Drilling strategy for drills > 12 × Dc:

  • Pre-drill a hole 1,5-2 × Dc. Use a solid cemented carbide drill with the same diameter; it is recommended to use a shallow point angle, 150°.
  • When entering with the long drill, start the machine spindle at a low speed not higher than 500 rpm, with no cooling.
  • Insert the drill into the hole, stopping about 1 mm above the bottom of the pre-drilled hole.
  • At full drilling depth, reduce the speed to 500 rpm and turn off the cutting fluid.
  • Retract the drill by 4 times the machine feed to avoid re-scratching the surface of the hole.

Long hole drilling, 16 – 20 × Dc. Cutting data by drill diameter. Columns give drill diameter, (Dc), mm / Feed per revolution, (fn), mm/rev.


Steel grade

Cutting speed (Vc), m/min

Ø 6,0 mm — Min - Max

Ø 6,0 mm — Start value

Ø 8,0 mm — Min - Max

Ø 8,0 mm — Start value

Ø 10,0 mm — Min - Max

Ø 10,0 mm — Start value

Ø 12,0 mm — Min - Max

Ø 12,0 mm — Start value

Toolox® 33

50 – 70

0,06 – 0,12

0,14

0,14 – 0,20

0,16

0,17 – 0,24

0,19

0,18 – 0,26

0,20

Toolox® 40

50 – 65

0,10 – 0,15

0,12

0,11 – 0,18

0,14

0,13 – 0,22

0,16

0,15 – 0,24

0,18

Toolox® 44

40 – 60

0,08 – 0,14

0,11

0,10 – 0,18

0,13

0,12 – 0,21

0,15

0,14 – 0,23

0,17

Exchangeable tip drills

A good first choice when drilling medium-sized holes. The exchangeable tip provides for an economical solution.

  • The drill has close hole tolerance.
  • The steel-made drill body provides the drill with toughness.
  • Used for short or relatively deep holes.

Exchangeable tip drill. Cutting data by drill diameter. Columns give drill diameter, (Dc), mm / Feed per revolution, (fn), mm/rev / Min - Max.


Steel grade

Cutting speed (Vc), m/min

Ø 7,5 – 12,0 mm

Ø 12,01 – 20,0 mm

Ø 20,01 – 25,0 mm

Ø 25,01 – 30,0 mm

Toolox® 33

50 – 80

0,10 – 0,16

0,15 – 0,23

0,18 – 0,27

0,20 – 0,30

Toolox® 40

50 – 65

0,08 – 0,15

0,12 – 0,22

0,15 – 0,25

0,17 – 0,27

Toolox® 44

40 – 60

0,08 – 0,14

0,12 – 0,20

0,14 – 0,22

0,16 – 0,25

Indexable insert drill

This drill produces holes at a low cost, due to the fact that it is possible to use several sides on the inserts. This drill has no tip that centers the drill, therefore use as short drills as possible to achieve good lateral stability when used in Toolox®.

  • Medium and large diameter holes.
  • Medium tolerance demands.
  • A drill suitable for boring operations.

The recommendations apply to a drill with a max drilling depth of 2 × Dc.

Indexable insert drill. Cutting data by drill diameter. Columns give drill diameter, (Dc), mm / Feed per revolution, (fn), mm/rev / Min - Max.


Steel grade

Cutting speed (Vc), m/min

Ø 12,0 – 20,0 mm

Ø 20,01 – 30,0 mm

Ø 30,01 – 40,0 mm

Ø 40,01 – 60,0 mm

Toolox® 33

80 – 140

0,04 – 0,12

0,06 – 0,16

0,08 – 0,20

0,10 – 0,21

Toolox® 40

70 – 130

0,04 – 0,12

0,06 – 0,16

0,08 – 0,20

0,10 – 0,21

Toolox® 44

60 – 110

0,04 – 0,12

0,06 – 0,16

0,08 – 0,20

0,10 – 0,21

HSS drills

Use HSS drills only when you have unstable machine conditions. If the machine conditions are good you can use a different solid cemented carbide drill or a drill with exchangeable tip.

Use an HSS-Co drill (8% Co) with a small helix angle and a robust core that can withstand high torques. Individual holes can be drilled with an ordinary HSS drill.

HSS-Co drill. Cutting data by drill diameter. Columns give drill diameter, (Dc), mm / Feed per revolution, (fn), mm/rev.


Steel grade

Cutting speed (Vc), m/min

Ø 5 mm

Ø 10 mm

Ø 15 mm

Ø 20 mm

Ø 25 mm

Ø 30 mm

Toolox® 33

≈ 15

0,10

0,10

0,16

0,23

0,30

0,35

Toolox® 40

≈ 9

0,05

0,10

0,16

0,22

0,28

0,35

Toolox® 44

≈ 7

0,05

0,09

0,15

0,20

0,25

0,30

Face milling cutter with indexable inserts machining Toolox®
Milling operation on a Toolox® workpiece

Milling recommendations

Clamping

Toolox® has a very low level of residual stresses. To get the full effect make sure to use deformation-free clamping. If blanks are gas cut, mill off 5-10 mm from the gas-cut edge to get a blank free from residual stresses.

The machinability of Toolox® has been improved. During milling you will notice it because the chips produced are very bluish. We have modified the carbide morphology as compared to traditional tool steels, using less carbon in Toolox®. Therefore, the heat generated during milling is transferred into the chip and not into the cutting edge/workpiece.

Comparison of insert wear after 800 passes using the roll-into-cut method against 390 passes going straight into the workpiece

Milling advice

  • Position the cutter off-centre (to the left) to achieve a thicker chip at the entry and to avoid a thick chip on the exit.
  • Avoid cutting through the center line of the cutter, because this can generate vibration.
  • Always use down milling (climb milling).
  • The recommendation is that the radial engagement of the cutter (ae) should be 25 or 75-80% of the diameter.

If you enter the workpiece with the roll-into-cut method, the chip thickness on the exit is always zero, and it will help to give a longer tool life. The programmed radius for roll-into-cut is Dc / 2 + 2.

Roll-into-cut. Wear after 800 passes with the roll-into-cut method, against wear after 390 passes going straight into the workpiece. Image: Sandvik Coromant AB.

Chart mapping ISO and ANSI carbide grade codes onto the P, M, K and H workpiece material classes with wear resistance and toughness directions

Insert grades for milling. ISO and ANSI grade codes against the P, M, K and H workpiece material classes, with the wear-resistance and toughness direction of the scale.

Comparison of edge strength, cutting forces, power consumption, chip thickness and heat generated for L, M and H insert geometries

Insert geometry. Edge strength, cutting forces, power consumption, maximum chip thickness and heat generated across the L, M and H geometries.

Face milling cutting data at a 45 degree entering angle for Toolox® 33, 40 and 44, with cutting speed and feed per tooth min-max and start values

Face milling recommendations

Face milling, 45° entering angle. Recommendations for average machine conditions, insert grade P30.

Face milling cutting data with round inserts for Toolox® 33, 40 and 44

Face milling, round insert. Recommendations for average machine conditions.

Shoulder and face milling cutting data for Toolox® 33, 40 and 44

Shoulder / face milling. Recommendations for average machine conditions.

High feed face milling cutting data for Toolox® 33, 40 and 44

High feed face milling. Recommendations for average machine conditions.

Slot milling and end milling cutting data by cutter diameter for Toolox® 33, 40 and 44

Slot milling and end milling. Recommendation for a solid cemented carbide tool, by cutter diameter.

Turning a Toolox® round bar on a lathe

Turning recommendations, Toolox® round bars

Formulas and definitions, turning

  • Vc = Dm × π × n / 1000
  • n = Vc × 1000 / (π × Dm)
  • vf = n × fn
  • π = 3,14
  • Vc = cutting speed (m/min)
  • n = spindle speed (rpm)
  • fn = feed per revolution (mm/r)
  • vf = feed rate (mm/min)
  • Dm = machined diameter (mm)
  • ap = cutting depth (mm)
Turning cutting data for roughing at 3 mm depth of cut and finishing at 1 mm, insert grade P15 to P25

Turning, roughing and finishing. Roughing at ap 3 mm and finishing at ap 1 mm, insert grade P15-P25.

Parting off cutting data for Toolox® round bars

Parting off. Cutting data for parting off Toolox® round bars.

Tapping a thread in a Toolox® component

Threading recommendations

Cutting speeds for tapping are 7 – 10 m/min for Toolox® 33, 4 – 9 m/min for Toolox® 40 and 3 – 5 m/min for Toolox® 44. The spindle speeds that follow from those are listed by thread size below.

Tapping. Spindle speed in rpm by thread size. Cutting speed Vc is 7 – 10 m/min for Toolox® 33, 4 – 9 m/min for Toolox® 40 and 3 – 5 m/min for Toolox® 44.


Size

Toolox® 33

Toolox® 40

Toolox® 44

M5

445 – 635

255 – 570

190 – 320

M6

370 – 530

210 – 475

160 – 265

M8

270 – 400

160 – 360

120 – 200

M10

220 – 320

125 – 285

95 – 160

M12

185 – 265

105 – 240

80 – 130

M16

140 – 200

80 – 180

60 – 100

M20

110 – 160

60 – 140

45 – 80

Cold forming tap cutting data, Toolox® 33 only, 5 to 20 m/min in sizes M6 to M12

Cold forming tap. Cold forming tapping is recommended for Toolox® 33 only, at 5 – 20 m/min in sizes M6 – M12.

Thread milling cutting speed and feed per tooth for Toolox® 33, 40 and 44

Thread milling. Cutting speed and feed per tooth by grade.

Recommendation counterboring and countersinking

Use a counterbore or countersink with indexable inserts. Feed per revolution is 0.10 – 0.20 mm/r for all three grades in both operations. The countersinking cutting speeds are 30% lower than the counterboring ones, in line with SSAB’s general rule for countersinking.

Counterboring. Spindle speed in rpm by counterbore diameter. Cutting speed Vc is 40 – 80 m/min for Toolox® 33, 25 – 70 m/min for Toolox® 40 and 20 – 50 m/min for Toolox® 44; feed per revolution 0.10 – 0.20 mm/r.


Dc

Toolox® 33

Toolox® 40

Toolox® 44

19 mm

670 – 1340

420 – 1175

335 – 840

24 mm

530 – 1060

330 – 930

265 – 665

34 mm

375 – 750

235 – 655

185 – 470

42 mm

300 – 600

190 – 530

150 – 380

57 mm

225 – 440

140 – 390

110 – 280

Countersinking. Spindle speed in rpm by countersink diameter. Cutting speed Vc is 28 – 56 m/min for Toolox® 33, 18 – 49 m/min for Toolox® 40 and 14 – 35 m/min for Toolox® 44; feed per revolution 0.10 – 0.20 mm/r.


Dc

Toolox® 33

Toolox® 40

Toolox® 44

19 mm

469 – 938

302 – 821

235 – 586

24 mm

371 – 743

239 – 650

186 – 464

34 mm

262 – 524

169 – 459

131 – 328

42 mm

212 – 424

136 – 371

106 – 265

57 mm

156 – 313

101 – 274

78 – 195

Tool recommendations for Toolox®

The tools below are grouped by type. Article numbers are reproduced exactly as SSAB prints them, including the wildcard characters that stand for the size-dependent part of the number. Similar tools from other suppliers might work; these are the ones SSAB has tested.

High speed steel drill. High speed steel drill alloyed with 8% cobalt (HSS-Co 8%). High speed steel drill standard. Only for Toolox® 33. High speed steel drill alloyed with cobalt (DRILL BIT COBALT”S”+X-ALCR DIN1897N HARDOX STUB). High speed steel drill alloyed with cobalt (DRILL BIT COBALT”S”+X-ALCR TAPER STUB).


Supplier

Tool name

Article nr

Web

Alpen-MayKestag, Austria

HSS-E Co 8 Taper Shank Drills, WN 103

832xxxxx

https://www.maykestag.com/en/

Witec, Germany

TYPE WITEC MN

2-135 15 VAP

http://witec-tools.de/index.php?content=produkte&lang=en

Dormer Pramet

HSS A100

A100xx.xx

https://www.dormerpramet.com/en-gb/pages/default.aspx?country=gb

Izar, Spain

Ref 1054

Article nr: 32xxx

https://www.izartool.com/

Izar, Spain

Ref 1154

xxxxx

https://www.izartool.com/

Solid cemented carbide drill. Solid cemented carbide drill. Solid cemented carbide drill. Long hole drilling with 16 – 20xD.


Supplier

Tool name

Article nr

Web

SECO TOOLS, Sweden

Seco Feedmax

SD203A-xx.xx-xx-xxxx-x

https://www.secotools.com/

Sandvik Coromant AB, Sweden

Corodrill® Delta-C

R840-xxxx-30-A1A

https://www.sandvik.coromant.com/

SECO TOOLS, Sweden

Seco Feedmax

SD216A-xx.xx-xx-xxxx-x

https://www.secotools.com/

Sandvik Coromant AB, Sweden

CoroDrill 861

861.1-xxxx-xxxxxx-xx

https://www.sandvik.coromant.com/

Indexable insert drill. Indexable insert drill.


Supplier

Tool name

Article nr

Web

Sandvik Coromant AB, Sweden

Corodrill 880

880-xxxxxxxx-xx

https://www.secotools.com/

Drill with exchangeable drill tip. Drill with exchangeable drill tip. Drill tip grade: IC908.


Supplier

Tool name

Article nr

Web

Iscar, Israel

Chamdrill

DCM xxx-xxx-xxA-xx

https://www.iscar.com/

Iscar, Israel

SumoCham

DCN xxx-xxx-xxA-xx

https://www.iscar.com/

Seco Tool AB, Sweden

Crownloc

SD103-xx.xx-xx-xxxx

https://www.secotools.com/

Taps. HSSE tap with TiCN coating. HSSE-PM tap with TiCN coating. HSSE-PM tap with TiN coating.


Supplier

Tool name

Article nr

Web

Emuge Franken, Germany

Rekord 1D-TI-TiCn, Rekord 2D-TI-TiCN

B0459601.xxxx, C0459601.xxxx

https://www.emuge-franken.se/en/

Manigley, Switzerland

131/3 DUO

433xx

http://manigley.ch/

Emuge Franken, Germany

Rekord 1C-TI-TiCn, Rekord 2C-TI-TiCN

B0309601.xxxx, C0309601.xxxx

https://www.emuge-franken.se/en/

Manigley, Switzerland

105/4 DUO

433xx

http://manigley.ch/

Emuge Franken, Germany

InnoForm2-Steel

C5267F00.xxxx

https://www.emuge-franken.se/en/

Thread milling cutters. Solid carbide thread milling cutter with TiCN coating. Solid carbide thread milling cutter with TiAlCN coating.


Supplier

Tool name

Article nr

Web

Emuge Franken, Germany

GSF-1,5xD-IKZ-HB-TiCN

GF333106xxxx

https://www.emuge-franken.se/en/

Smicut, Sweden

Solid Carbide Thread Mill

NBxxxxxCxxx.xISO AC

https://smicut.com/en/

Counterbore and countersink. Use counterbore with indexable inserts that always have a grade number ending in U. Use countersink with indexable inserts that always have a grade number ending in U.


Supplier

Tool name

Article nr

Web

Granlund Tool AB, Sweden

WHV Counterbore

xWHV-xx.x

http://www.granlund.com/

Granlund Tool AB, Sweden

KV Countersink

xKV9-xx.x

http://www.granlund.com/

End milling. Solid end milling cutter with Siron-A coating.


Supplier

Tool name

Article nr

Web

Seco Tool AB, Sweden

JS 554 Siron-A

JS 554 xxxx

https://www.secotools.com/

Milling with inserts. Face milling with Coromill 345. Face milling with Coromill 300. Shoulder/Face milling with Coromill 490. Face milling with Mill4Feed. Face milling with Coromill 210.


Supplier

Tool name

Article nr

Insert grade

Web

Sandvik Coromant AB, Sweden

Coromill 345

345-xxxxxx-13x

1030

https://www.sandvik.coromant.com/

Sandvik Coromant AB, Sweden

Coromill 300

R300-xxxxxx-xxx

1030

https://www.sandvik.coromant.com/

Sandvik Coromant AB, Sweden

Coromill 490

490-xxxxxx-xxx

1030

https://www.sandvik.coromant.com/

Iscar, Israel

Mill4Feed

FFQ4 xxxx-x-xxx-xx

IC808

https://www.iscar.com/

Sandvik Coromant AB, Sweden

Coromill 210

210-xxxxxx-xxx

1030

https://www.sandvik.coromant.com/

Contact and more information

Contact your local SSAB representative or Tech Support at [email protected], or visit www.toolox.com.

All content in this brochure should be considered as recommendations. Optimization of cutting data should always take place at the machine to be used for manufacturing.