Damatech
High Performance SteelValue Added ProcessingInnovative Industrial SolutionsDamatech

Armox® Machining

Radial column drilling machine

Machining recommendations

Drilling

Drilling can be performed using high-speed steel drills or cemented carbide drills. When drilling in Armox® with HSS drills in radial/column drilling machines the first choice is a HSS-Co 8% drill with a small helix angle; for individual holes you can use an ordinary HSS drill.

High-speed steel twist drill with a taper shank

Advice for reducing vibrations and increasing the lifetime of the drill — HSS drill, max drill length 3 × diameter:

  • Minimize the distances to the column and between the drill tip and the workpiece.
  • Don’t use a longer drill than necessary.
  • Always use metal supports.
  • Clamp securely.
  • Solid and firm table.
  • Use coolant.
  • Just before the drill breaks through, disengage the feed rate for about a second; play/spring back can otherwise snap the drill tip. Re-engage the feed rate when the play/spring back has ceased.

Table 5. HSS drill (max drill length 3 × diameter). Drill diameter (Dc) columns give the feed per revolution (fn) in mm/rev.


Steel grade

Cutting speed (Vc), m/min

Ø 10 mm

Ø 15 mm

Ø 20 mm

Ø 30 mm

Armox® 370T, CL 1 & 2

7 – 10

0,10

0,16

0,23

0,35

Armox® 440T

5 – 7

0,09

0,14

0,20

0,30

Armox® 500T

3 – 5

0,08

0,12

0,16

0,24

Solid cemented carbide drill with a coated tip

Drilling recommendations when the machine conditions are good

Solid cemented carbide drill, max drill length 3 × diameter.

Table 6. Solid cemented carbide drill (max drill length 3 × diameter). Drill diameter (Dc) columns give the feed per revolution (fn) in mm/rev.


Steel grade

Cutting speed (Vc), m/min

Ø 3,0–5,0 mm

Ø 5,1–10,0 mm

Ø 10,01–15,0 mm

Ø 15,01–20,0 mm

Armox® 370T, CL 1 & 2

60–80

0,03–0,06

0,06–0,12

0,12–0,17

0,17–0,22

Armox® 440T

40–60

0,03–0,05

0,05–0,11

0,11–0,15

0,15–0,20

Armox® 500T

35–60

0,03–0,05

0,05–0,10

0,10–0,14

0,14–0,18

Armox® 520T

35–60

0,03–0,05

0,05–0,10

0,10–0,14

0,14–0,18

Armox® 560T

30–40

0,03–0,05

0,05–0,09

0,09–0,13

0,13–0,17

Armox® 600T

25–35

0,02–0,04

0,04–0,08

0,08–0,13

0,13–0,16

Armox® 620T

25–35

0,02–0,04

0,04–0,08

0,08–0,13

0,13–0,16

Armox® Advance

18–25

0,02–0,04

0,04–0,08

0,08–0,12

0,12–0,15

Two exchangeable-tip drills

Exchangeable-tip drill, max drill length 3 × diameter.

Table 7. Exchangeable-tip drill (max drill length 3 × diameter). Feed per revolution (fn) in mm/rev.


Steel grade

Cutting speed (Vc), m/min

Ø 12,0–20,0 mm

Ø 20,1–30,0 mm

Ø 30,01–44,0 mm

Ø 44,01–63,0 mm

Armox® 370T, CL 1 & 2

60–120

0,04–0,10

0,06–0,12

0,06–0,14

0,08–0,16

Armox® 440T

50–90

0,04–0,10

0,06–0,12

0,06–0,14

0,08–0,16

Armox® 500T

40–70

0,04–0,08

0,04–0,10

0,06–0,12

0,08–0,14

Armox® 520T

40–70

0,04–0,08

0,04–0,10

0,06–0,12

0,08–0,14

Armox® 560T

35–55

0,04–0,08

0,04–0,10

0,06–0,12

0,08–0,14

Armox® 600T

30–50

0,04–0,06

0,04–0,08

0,06–0,10

0,06–0,12

Armox® 620T

30–50

0,04–0,06

0,04–0,08

0,06–0,10

0,06–0,12

Table 8. Indexable insert drill (max drill length 2 × diameter). Feed per revolution (fn) in mm/rev. The brochure prints the same values here as in Table 7.


Steel grade

Cutting speed (Vc), m/min

Ø 12,0–20,0 mm

Ø 20,01–30,0 mm

Ø 30,01–44,0 mm

Ø 44,01–63,0 mm

Armox® 370T, CL 1 & 2

60–120

0,04–0,10

0,06–0,12

0,06–0,14

0,08–0,16

Armox® 440T

50–90

0,04–0,10

0,06–0,12

0,06–0,14

0,08–0,16

Armox® 500T

40–70

0,04–0,08

0,04–0,10

0,06–0,12

0,08–0,14

Armox® 520T

40–70

0,04–0,08

0,04–0,10

0,06–0,12

0,08–0,14

Armox® 560T

35–55

0,04–0,08

0,04–0,10

0,06–0,12

0,08–0,14

Armox® 600T

30–50

0,04–0,06

0,04–0,08

0,06–0,10

0,06–0,12

Armox® 620T

30–50

0,04–0,06

0,04–0,08

0,06–0,10

0,06–0,12

Counterboring tool with replaceable carbide inserts and a revolving pilot

Countersinking and counterboring

Countersinking and counterboring are best performed using tools which have replaceable inserts. Always use a revolving pilot and use coolant.

Table 9. Counterboring and countersinking (tool supplier: Granlund Tools). Counterbore diameter (Dc) columns give the feed per revolution (fn) in mm/rev.


Steel grade

Cutting speed (Vc), m/min

Ø 18,0–26,0 mm

Ø 26,00–38,0 mm

Ø 38,00–47,0 mm

Ø 47,00–60,0 mm

Armox® 370T, CL 1 & 2

20–80

0,10–0,20

0,10–0,20

0,06–0,14

0,08–0,16

Armox® 440T

20–50

0,10–0,20

0,10–0,20

0,06–0,14

0,08–0,16

Armox® 500T

15–45

0,10–0,20

0,10–0,20

0,06–0,12

0,08–0,14

Armox® 520T

15–45

0,10–0,20

0,10–0,20

0,06–0,12

0,08–0,14

Armox® 560T

10–40

0,10–0,20

0,10–0,20

0,06–0,12

0,08–0,14

Armox® 600T

10–35

0,10–0,20

0,10–0,20

0,06–0,10

0,06–0,12

Armox® 620T

10–35

0,10–0,20

0,10–0,20

0,06–0,10

0,06–0,12


Important: reduce the cutting data by about 30 % for countersinking.

Counterboring tool head seen from the insert side

Milling

To ensure rational production, milling cutters with cemented carbide inserts are recommended. Keep this in mind:

  • Position the cutter off-centre (to the left) to achieve a thicker chip at the entry and to avoid a thick chip on the exit.
  • Cutter diameter should be 20–50 % larger than the width of cut, ae.
  • Avoid centring the cutter on the centre line — that will generate more vibrations.
  • Always use down milling (climb milling).

Table 12. Face milling.


Steel grade

Cutting speed (Vc), m/min

Feed per tooth (fz) min, mm/tooth — insert grade P20–P30

Feed per tooth (fz) max, mm/tooth — insert grade P20–P30

Armox® 370T, CL 1 & 2

100–175

0,1

0,2

Armox® 440T

50–80

0,1

0,2

Armox® 500T

50–70

0,1

0,2

Armox® 520T

50–70

0,1

0,2

Armox® 560T

35–60

0,1

0,2

Armox® 600T

30–55

0,07

0,15

Armox® 620T

30–55

0,07

0,15

Armox® Advance

25–40

0,07

0,15

Tapping and thread milling

With the correct tools, all tapping and thread milling can be performed in all Armox® grades. We recommend four-flute taps which can withstand the very high torque which occurs during tapping in hard materials. If the strength is not critical, the drilled hole can be 3 % larger than standard, which will increase the lifetime of the tap.

Table 10. Tapping.


Steel grade

Cutting speed (Vc), m/min

Size from–to

Armox® 370T, CL 1 & 2

1–5

M6–M30

Armox® 440T

1–5

M8–M30

Armox® 500T

1–5

M10–M30

Table 11. Thread milling.


Steel grade

Cutting speed (Vc), m/min

Feed per tooth (fz), mm/tooth

Armox® 370T, CL 1 & 2

40–120

0,02–0,05

Armox® 440T

40–120

0,02–0,05

Armox® 500T

30–60

0,015–0,04

Armox® 520T

30–60

0,015–0,04

Armox® 560T

30–60

0,005–0,025

Armox® 600T

30–40

0,005–0,025

Armox® 620T

30–40

0,005–0,025

Armox® Advance

25–35

0,005–0,015


To manage thread milling, a CNC machine with a minimum of 3 axes is necessary and the thread should be made in two passes.

Contact and more information

Contact your local SSAB representative or Tech Support at [email protected], or visit www.ssab.com.

This leaflet contains general suggestions and calculation models. It is the responsibility of the user to adapt the recommendations contained herein to the requirements of individual applications.